湍流模型跨版本（2.1.1与2.3.1）编译问题-已解决

[一颗鸭蛋]

最近需要将2.1.1版本下开发的湍流KOmegaMDH 模型添加到2.3.1中，直接在如下根目录下新建文件夹KOmegaMDH将KOmegaMDH.C和KOmegaMDH.H放进去，

2.3.1/src/turbulenceModels/incompressible/RAS

在Make/files 中添加’KOmegaMDH/KOmegaMDH.C’并保存，在RAS下运行wclean和wmake libso 自动将库模型全部更新一遍，但编译到KOmegaMDH模型时便会报如下错误：

    error:invalid new-expression of abstruct class type 'FOAM::incompressible::RASModels::KOmegaMDH'   //出现这个错误原因是new 了一个抽象类出错，说明父类（接口）中有纯虚函数没有实现。接口里的纯虚函数全部需要实现，这样才能new 子类。https://www.cnblogs.com/laizhenghong2012/p/11302657.html(参考此文档解释)
    
        return auto<basseType>(new baseType##Type parlist); 
                                                         ^
/home/kdd/OpenFOAM/OpenFOAM-2.3.1/src/turbulenceModels/incompressible/RAS/lnInclude/RASModel.H:125:9: note: in expansion of macro 鈥榙eclareRunTimeSelectionTable鈥?         declareRunTimeSelectionTable
               ^
In file included from kOmegaMHD.C:26:0:
kOmegaMHD.H:77:7: note:   because the following virtual functions are pure within 'Foam::incompressible::RASModels::kOmegaMHD':
                class kOmegaMHD
                      ^
In file included from /home/kdd/OpenFOAM/OpenFOAM-2.3.1/src/turbulenceModels/incompressible/RAS/lnInclude/RASModel.H:47:0,
             from kOmegaMHD.H:62,
             from kOmegaMHD.C:26:
/home/kdd/OpenFOAM%(#804e4e)[/OpenFOAM-2.3.1/src/turbulenceModels/incompressible/turbulenceModel/turbulenceModel.H:217:37]: note: 	virtual Foam::tmp<Foam::fvMatrix<Foam::Vector<double> > > Foam::incompressible::turbulenceModel::divDevRhoReff(const volScalarField&, Foam::volVectorField&) const  //这里才是最关键，显示这个H文件里217行有个虚函数const=0没有实现
     virtual tmp<fvVectorMatrix> divDevRhoReff
                                 ^

找到/OpenFOAM-2.3.1/src/turbulenceModels/incompressible/turbulenceModel/turbulenceModel.H 并将这个H文件打开找到217行如下：

  213  //- Return the source term for the momentum equation
  214 virtual tmp<fvVectorMatrix> divDevReff(volVectorField& U) const = 0;
  215 
  216 //- Return the source term for the momentum equation
  217  virtual tmp<fvVectorMatrix> divDevRhoReff
       (
            const volScalarField& rho,
            volVectorField& U
        ) const = 0;
    //- Solve the turbulence equations and correct the turbulence viscosity
    virtual void correct() = 0;

发现在2.3.1版本下的湍流模型的H文件中有两个同样的//- Return the source term for the momentum equation （213行和217行）
再找到/OpenFOAM-2.1.1/src/turbulenceModels/incompressible/turbulenceModel/turbulenceModel.H 发现只有一个//- Return the source term for the momentum equation ，如下：

   //- Return the source term for the momentum equation
    virtual tmp<fvVectorMatrix> divDevReff(volVectorField& U) const;          
   //- Solve the turbulence equations and correct the turbulence viscosity
    virtual void correct();

所以正确的做法是在KOmegaMDH.H文档中再添加一个与2.3.1相同的//- Return the source term for the momentum equation 函数，添加如下内容：

   //- Return the source term for the momentum equation
    virtual tmp<fvVectorMatrix> divDevReff(volVectorField& U) const;

    //- Return the source term for the momentum equation
    virtual tmp<fvVectorMatrix> divDevRhoReff
    (
        const volScalarField& rho,
        volVectorField& U
    ) const;    //添加这个函数，你也可以在查看2.3.1中其他模型下的H文档与2.2.1的进行对比，就能发现其中差异。

    //- Solve the turbulence equations and correct the turbulence viscosity
    virtual void correct();

然后点击保存，再运行wclean和wmake libso 就可以了，希望可以帮到其他小伙伴~

[Samuel-Tu]

感谢楼主分享

[李东岳]

感谢楼主分享